Constraint Tangent |
Menu location |
---|
Sketch → Sketcher constraints → Constrain tangent |
Workbenches |
Sketcher, PartDesign |
Default shortcut |
None |
See also |
Constraint point on object |
Tangent Constraint makes two curves to touch each other (be tangent). Lines are treated infinite, and arcs are treated as full circles/ellipses. The constraint is also capable of connecting two curves, forcing them tangent at the joint, thus making the joint smooth.
There are four different ways the constraint can be applied:
To apply tangent constraint, one should the follow the steps:
Two curves will be made tangent, and the point of tangency will be implicit. This mode is applied if two curves were selected.
Accepted selection:
If direct tangency between selected curves is not supported (e.g. between a circle and an ellipse), a helper point will be added to sketch automatically, and tangency-via-point will be applied.
It is not recommended to reconstruct the point of tangency by creating a point and constraining it to lie on both curves. It will work, but the convergence will be seriously slower, jumpier, and will require about twice as many iterations to converge than normal. Use other modes of this constraint if the point of tangency is needed.
In this mode, the endpoints are made coincident, and the joint is made tangent (C1-smooth, or "sharp", depending on the placement of curves before the constraint is applied). This mode is applied when two endpoints of two curves were selected.
Accepted selection:
In this mode, an endpoint of one curve is constrained to lie on the other curve, and the curves are forced tangent at the point. This mode is applied when a curve and an endpoint of another curve were selected.
Accepted selection:
In this mode, two curves are made tangent, and the point of tangency is tracked. This mode is applied when two curves and a point were selected.
Accepted selection:
"Any point" can be a lone point, or a point of something, e.g. a center of a circle, an endpoint of an arc, or the origin.
For the constraint to work correctly, the point must be on both curves. So, as the constraint is invoked, the point will be automatically constrained onto both curves (helper constraints will be added, if necessary), and the curves will be forced tangent at the point. These helper constraints are plain regular constraints. They can be added manually, or deleted.
Compared to direct tangency, this constraint is slower, because there are more degrees of freedom involved, but if the point of tangency is needed, it is the recommended mode because it offers better convergence compared to direct tangency + point on two curves.
The placement of the point before the constraint is applied is a hint for the solver for where the tangency should be. With this constraint, one can constrain two ellipses to touch each other in two places.
Tangent Constraint can be created from macros and from the python console by using the following:
# direct tangency Sketch.addConstraint(Sketcher.Constraint('Tangent',icurve1,icurve2)) # point-to-point tangency Sketch.addConstraint(Sketcher.Constraint('Tangent',icurve1,pointpos1,icurve2,pointpos2)) # point-to-curve tangency Sketch.addConstraint(Sketcher.Constraint('Tangent',icurve1,pointpos1,icurve2)) # tangent-via-point (plain constraint, helpers are not added automatically) Sketch.addConstraint(Sketcher.Constraint('TangentViaPoint',icurve1,icurve2,geoidpoint,pointpos))
where: